Third Trunnion Operation

Now we’ve mounted the fixture used in operation two onto the 4th axis (rotary). The part is again bolted and pinned to the fixture, and this arrangement allows us to machine the main bore and also rotate the part to 90, 180, and 270 degrees to add mounting holes, threads, etc. (Please forgive the rust visible on the 4th axis unit. It’s gone now, thanks to an Ospho(tm) phosphoric acid treatment that completely fixes the problem.)

Part mounted for 4-axis boring and drilling

I roughed the main bore using a 3/4″ diameter drill from both sides, followed by a 1-1/4″ stub drill from both sides, then an endmill using circular interpolation to get within .010″ of the final size. Finish boring was with a fancy Wohlhaupter boring head, which allowed us to bore 6″ deep and hold roundness and size with .0002″. A real pleasure to use a beautifully balanced tool like that.

Finish Machining the Bore

The next picture shows the boring tool in operation, with the usual coolant squirting everywhere. Must have cooling and lubrication. The threads were cut earlier with a thread mill using helical milling. (I made a thread plug gauge previously to check the thread size as we finished it). Boring was the last step, so we could make necessary fine size adjustments and repeat the operation as necessary.

The Mill in operation- can’t see much…

We used a boring cycle on the Fadal Mill that bores to depth, stops the spindle, shifts slightly away from the work, then retracts out of the hole. This is more accurate and leaves a better finish than the usual “G85 bore-in, bore-out” cycle. Most CNC machines have something similar.

Inspecting the bore with press fit bearings

This shows the finished bore, after the part has been anodized (Type I), and we have pressed two IGUS(tm) plastic bearings into the bore. The grooves visible in the bearings are to prevent hydraulic fluid from locking and possibly shifting the bearings.

Trunnion Second Operation

Preparing to machine the second side

This shows the preparation for the second operation. We have bolted our fixture plate down to the mill bed and aligned the dowel pins parallel to the X-axis. The use of precision dowel holes put in during the first operation allows us to maintain control of where we are when we turn the part over. The part is held down by 4 socket head capscrews and aligned on 2 dowel pins. The screw heads are deeply counterbored into the part so we can machine most of the shape without hitting the screws.  This type of fixturing is very robust and accurate. The same fixture we’re using here will also be used to hold the part when it is mounted on the rotary (4th) axis.

After machining the second side

This shows the part after we’ve finished machining the second side. Now the basic “profile” is complete except for removing the holding tabs which will happen later. Notice that the capscrews are now visible just below the cut surface, so we removed quite a bit of the holding tab with these cuts. This was done with a high-helix 3-flute carbide endmill which roughs and finishes quickly, and a 1/2″ carbide ball endmill which created the cylinder shape and the floor area of the two pockets. We are using SmartCam Freeform Machining software to create the toolpath from a model made in Solidworks.